Tool Path Parameters
Surface quality
In Rotary Machining, the Surface quality tab similar to the Surface quality tab of other Sim 5-Axis Milling operations except for the option of Step down.
Step down
This option enables you to define the step down as Constant Step Down or Maximum Step Down to adapt the cut level step according to automatic detected flatland level. The Flatland detection enhances the current material removal between the stock and workpiece geometry by adapting the cut level step according to the automatically detected flatland level. This option allows you to maintain the user defined max. value however, it reduces the depth step to the detected flatland.
The Distance parameter allows you to set the constant or the maximum step down distance.
When the option of Maximum Step Down is selected, the Min. distance (%) parameter is enabled This option allows you to set the value which defines the maximum portion by which the depth-step reduces.
Additional cuts -This option enables you to perform additional cuts with a defined Step down.
|
The options of Scallop and Tool diameter % are available only when Ball Nose Mill tool is selected. The option of Maximum step over is available only when the Strategy is selected as Roughing on the Geometry page. |
Sorting
In Rotary Machining, the Sorting tab similar to the Sorting tab of Geodesic Machining operations. This tab is available only with the options of One Way and Zigzag Cutting method and Direction for closed cuts.
Adaptive stepdown
Selecting this check box enables you to define Constant Stepdown or Number of slices parameters.
When you select the Constant Stepdown option, starting from the Upper level, SolidCAM uses the specified step down to calculate each successive Z-level.
When the Number of slices option is selected it enables you to define the number of slices by which the step down is performed between two roughing cuts. The distance of the slices is determined automatically.
The Detect thicker than option enables you to filter the generated intermediate slices which do not satisfy the specified threshold value condition.
Smoothing
Rotary machining allows you to apply corner rounding on Sharp Motions on the final contour as well as intermittent contours. This allows the machines to cut faster and improve the tool life.
Corners %
The feature will create fillets in the sharp corners of the tool path for all inner contours. The output radius value will be a percentage of the stepover distance.
Final Contour %
The feature will create fillets in the sharp corners of the tool path for the outer contour. The output radius value will be a percentage of the stepover distance.