Geometry

The Geometry tab enables you to define the values of several Geometry parameters. The Geometry tab contains the following options:

Strategy

Roughing

This strategy enables you to create the roughing tool path.

Pattern type

The Roughing strategy for Rotary Machining can be set with two patterns : Offset, Offset and Spiral.

• Offset pattern defines parallel steps along the rotational axis on the entire machined surface.
• Offset and Spiral pattern combine two types of slicing. The process automatically chooses spiral cuts based on machined conditions. The tool can perform spiral cuts only in a safe condition, without collisions.

Finishing

This strategy enables you to create the finishing tool path.

Machining surfaces

The Machining surfaces are the entire model or any surface(s) of the design model.

enables you to define a new 3D Model geometry for the operation with the 3D Geometry dialog box.

enables you to edit an existing geometry.

enables you to view the available geometries on the model and choose the relevant one from the list.

Show button displays the Show Geometry dialog box and the Machining surfaces are displayed and highlighted in the graphic window.

Offset- The Offset parameter allows you to define the offset for the Machining surfaces.  

Side shift

This option allows rotary machining with Side shift. It is available only when the Strategy is selected as Roughing. This option enables the tool to cut properly using the cutting edges and not the tool center. Therefore, you can achieve more stable cutting speeds and close-to-diameter cutting with non-spherical tools. The offset is always in the opposite direction to the direction of rotation and automatically changes position if the rotation direction changes. This changing movement is a linear movement without rotation. This prevents damage to the tool and ensures a safe process.

The Offset value activates or deactivates Side shift machining. The Offset value can be specified as a value in inch/mm or Tool diameter in %. The maximum acceptable Offset value is 50% of the Tool diameter. If you enter a negative value or a value more than 50% of Tool diameter the following error message is displayed:  

Machining area

The Machining area parameter allows you to limits the machining area using axial and angular limits.

Axial limits

Selecting the Axial limits check box enables you to set the Start distance and End distance values.

Start distance: The generated tool path starts at the distance defined across the rotary axis.

End distance: The generated tool path does not go beyond the specified end distance value.

Radial limits

The Radial limits parameter allows you to set Start distance and End distance value to define the radial machining area. When you select this check box and set the desired values, the tool path is calculated only in between these values.