Technology page
This page enables you to define the technological parameters of Face Milling.
Technology
SolidCAM provides you with the following strategies for face milling:
The machining is performed in a linear pattern.
The machining is performed in a number of equidistant contours.
SolidCAM performs the face milling in one pass.
The machining is performed in a spiral pattern.
Overlap/Min. Overlap
This section enables you define the tool overlapping between two successive passes.
This section defines the Overlap of adjacent tool paths in the milling of the pocket. It can be defined as a Percentage of the tool diameter or as a Value.
|
This section is available only for Hatch and Contour strategies. |
This option enables you to generate the hatch tool path spaced evenly with the automatically calculated Overlap value, which is nearest to the specified Min. Overlap value but not smaller than this value.
When this check box is not selected, the distance between the last pass and the one before it can be smaller than that between all of the other passes.
When this check box is selected, the evenly spaced hatch tool path is generated. The overlap between two successive passes is not smaller than the specified Min. Overlap value.
|
This option is available only for the Hatch strategy. |
This option is selected when you want to have the first and last tool path with equal width extension. When using this option enable the Equal Step over option. This option will be enabled by default when opening/converting an old CAM-Part .
Offsets
Floor Offset - This section enables you to define the offset for machining the remaining material on the face floor after the roughing operation.
Finish- Select this check box to remove the remaining offset material with the last cut. Unselect this check box to leave the offset unmachined for further operations.
Floor finish only- Select this check box to apply tool path only on the finish level using the Feed and Spin rates defined for Finish. Selecting this check box disables the Finish field which is checked automatically.
Depth Cutting Type
This option enables you to connect cutting passes by vertical zigzag movements. When a cutting pass is machined, the tool moves down to the next cutting level and machines it in the opposite direction. When the machining of all cutting levels is finished for a specific pass, the tool moves to the next cutting pass and machines it in the same manner.
More...
|
This section is available only for the Hatch and One Pass strategies. |
Reverse tool path
The Reverse check box enables you to reverse direction of the tool path. When this check box is selected, the hatch tool path is performed in the opposite direction.
Sort cut order
Complete Z-level
This option enables you to define the order of the machining Z-levels, in case more than one face is machined.
Optimized multi-chain cutting
This option enables you to use a special algorithm that optimizes the tool path linking and reduces unnecessary air cutting.
|
This option is available only for the Hatch and One Pass strategies. |
Related Topics